Skip to content
CNC Cut

File Setup

Files that cut first time.

Clean files cut faster, quote quicker and cost less. Follow this guide and your parts go from inbox to machine bed without a redraw.

01Accepted File Formats

TypePreferredAlso accepted
2DDXFDWG, AI, SVG, EPS
3DSTEP / STP3DM (Rhino), Fusion 360

Not accepted

STL, OBJ or any images (JPG, PNG, TIFF). These can't be converted to reliable toolpaths.

Scale must be 1:1 with all measurements in millimetres. If your part is 500mm long, it must measure 500 units in the file.

02Clean Geometry

  • All contours must be closed. A profile cut needs a single, continuous, closed vector. If a contour isn't closed, the toolpath stops short and the part won't cut correctly.
  • No duplicate entities. Delete any lines or points stacked on top of each other.
  • Convert all text to outlines/curves. We can't read font files.
  • Explode blocks and groups. We need raw, plain vectors.
  • Send files that contain only the parts to be cut: remove notes, dimensions, borders, title blocks and unused geometry.

032D File Setup

Create a separate layer for each cutting operation, named for what it does:

  • PROFILE_THROUGH: full-depth profile cuts
  • POCKET_12MM_DEEP: pockets with depth in the name
  • DRILL_8MM: drilling operations by diameter
  • ENGRAVE_TEXT: engraving
  • NOTES_IGNORE: anything we shouldn't cut

Keep all geometry near the origin (0,0) and delete stray points or lines far away from your parts.

File naming

ProjectName_Material_Thickness_Quantity_Revision.dxf, e.g. JonesKitchen_18mmBirchPlywood_x12_v2.dxf. Always include total quantities when nesting multiple parts in one file.

043D File Setup

Your 3D model is the single source of truth. We machine exactly what we see. Include only the solid bodies to be machined and delete all fixtures, hardware, mates, joints and reference geometry.

  • One solid body = one part. Multiple parts must each be a separate, watertight solid body.
  • Avoid complex assemblies with joints and constraints. They don't translate well.
  • Design for a 3-axis machine: we cut from the top down. No undercuts (e.g. dovetail profiles in the vertical plane), no horizontal holes in vertical faces, no overhangs or internal cavities.
  • State quantities in the filename or body name, e.g. JonesKitchen_DrawerFront_18mmMDF_x8.step.

05Internal Corners & Dog-Bones

A round router bit cannot cut a sharp 90° internal corner. It's a physical impossibility. With our standard 8mm cutter, every internal corner naturally carries a 4mm radius.

Where mating parts need to slot together, add a dog-bone corner: a small relief cut extending just past the corner that completely clears the material.

  • Draw them yourself: add correctly sized dog-bones directly in your CAD file, or
  • Ask us to do it: state "Please add dog-bone corners" in your quote request.

Important

If your design needs sharp internal corners and you neither draw dog-bones nor ask us to add them, we'll leave the corners rounded at 4mm radius, assume it's design intent, and are not responsible for parts that don't fit.

06Tolerances & Material Thickness

Sheet materials vary. MDF is usually consistent and close to its stated thickness; plywood often varies by 0.2-0.7mm, even within one sheet. When we supply the material, we measure it before cutting.

MaterialTypical tolerance
MDF±0.3mm
Plywood / Formply±0.3-0.7mm

Our standard fit clearance is 0.4mm total (0.2mm each side). An 18mm tab goes into an 18.4mm slot. Either draw the clearance into your design, or ask us to "add 0.2mm clearance each side for fit". If you say nothing, we cut exactly as drawn.

07Nesting & Sheet Layouts

The easiest method: send individual part files with quantities and we'll nest them to maximise material yield.

If you supply pre-nested sheets:

  • Leave a minimum 10mm border from the sheet edge.
  • Maintain a minimum 10mm gap between all parts.
  • Don't cram small parts: as material is removed the sheet loses vacuum hold and rigidity.
  • You take responsibility for material yield, part quantities and any manufacturing issues; we cut the file as supplied.

08Machine Capabilities

  • Standard cutters: Ø6mm and Ø8mm are the workhorses for general profiling.
  • Holes: drilled to size. Common sizes are 8, 8.5, 10 and 12mm; tell us the size you need, as other sizes may need a bit ordered in.
  • Thinnest wall or slot: at least the diameter of the tool being used.
  • Holding: parts are held with an onion skin and a finishing pass, so most need no tabs. Small parts may get tabs; mark any no-tab faces on a NOTES layer.
  • Machined from the top face only: no double-sided machining, undercuts or horizontal holes.
  • Grain direction: if it matters, mark it with an arrow.

09Pre-flight checklist

0 / 9 checks complete

Files ready to go?

Describe the job and drop in your plans or DXFs. We check it with you, then the team quotes it.